I want to model torsion of a homogeneous hollow cylinder in ANSYS. I changed to cylindric coordinate system also. But each time I run the program the result is that of bending. I have attached the mac file and output file for reference. Please advise.
finish
/clear
/PREP7
!*
ET,1,SOLID92
!*
!*
MPTEMP,,,,,,,,
MPTEMP,1,0
MPDATA,EX,1,,70e9
MPDATA,PRXY,1,,0.3
CSYS,1
CYL4,0,0,1, ,2, ,10
/USER, 1
/VIEW, 1, -0.308622066883 , 0.922501876538E-01, 0.946700756687
/ANG, 1, -1.01797039482
/REPLO
/DIST,1,1.08222638492,1
/REP,FAST
/DIST,1,1.08222638492,1
/REP,FAST
/DIST,1,1.08222638492,1
/REP,FAST
TYPE, 1
MAT, 1
REAL,
ESYS, 0
SECNUM,
!*
MSHAPE,1,3D
MSHKEY,0
!*
ESIZE,.1,0,
There are many
There are many approaches to simulating the torsion of a model in ANSYS.
Please see the code below (MPC method)
/PREP7
ET,1,95
et,2,184
keyopt,2,1,1
R,1,1E-6
MP,EX,1,2.01e5
MP,PRXY,1,0.3
CYLIND,15,10,0,200,0,360,
wpro,,90,
vsbw,all
wpro,,,90
vsbw,all
WPCSYS,-1,0
K,17 , , ,210
lsel,s,,,13,16,1
lesize,all, , ,8, , , , ,1
lsel,s,,,22
lesize,all, , ,4, , , , ,1
lsel,s, , ,17,20,1
lsel,a, , ,26,27,1
lsel,a, , ,30,31,1
lesize,all, , ,20,0.4, , , ,1
alls
vmesh,all
nsel,s,loc,z,200
n,15000 ,0,0,210
type,2
*get,nnum,node,0,count
*get,ND,node,0,num,min
*do,i,2,nnum
E, 15000,ND
ND=NDNEXT(ND)
*enddo
allsel
/SOLU
f,node(0,0,210),mz,10e5
nsel,s,loc,z,0
d,all,all
allsel
solve